SOLIDWORKS Multi-sheet Custom Properties Source
Multi-sheet Custom Properties Source
Drawing annotations can be linked to SOLIDWORKS Custom Properties of models in specific views. This is particularly helpful for drawings with multiple sheets of different models.
By default, SOLIDWORKS drawings are set to use custom properties from the current document. Switching the Linked to property options to ‘Model found here’ and ‘Drawing view specified in Sheet Properties’ uses the custom properties from a view on that sheet. You will also need to select a specific Property name as the linked Property name.
The Sheet Properties by default is set to use the properties from the model in the drawing view which was first added to the sheet ‘Default’. You can, however, choose any view on that sheet to link custom properties from the pulldown menu. Pro-tip, you can name your views by slowly double-clicking the view in the FeatureManager Design Tree of the drawing.
If you have a multi-sheet drawing with each sheet referencing different models, the first view is the source for the custom properties by default. In the example below, Sheet1 has a view of ‘CONVEYOR’, and the annotation is linked to the Filename of the model in the default view.
Sheet2 contains views of the part ‘CONVEYOR FRAME’. By default, the annotations linked to custom properties are pulling from the first drawing view added to the sheet, which is ‘CONVEYOR FRAME’.
If the linked custom properties on additional sheets are referencing the model in the views from the first sheet, you may need to disable an option in the Document Properties, which forces linked annotations on all sheets to reference the property of a specific sheet in the Document Properties. In some instances, this may be the desired option for a title block or annotations that should display the same information on each sheet even though some sheets may have views of different models.
Tools > Options > Document Properties > Drawing Sheets > Multi-sheet custom properties source, disable or modify the sheet number for option ‘Use custom property values from this sheet on all sheets.’
You also have the ability to override the custom property link on each individual sheet to have a combination of the settings from above. Edit the Sheet Properties and uncheck ‘Same as sheet specified in Document Properties’ and then select a specific view on the sheet or leave it as ‘Default’ to use the first view placed on the sheet.
Review the technical guides below to learn more about SOLIDWORKS Drawing Templates and Sheet Formats:
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